ANSYS 12 - Beam - Step 5

Step 5: Solution

Now that we have set up the boundary conditions, we can actually solve for a solution. Before we do that, let's take a minute to think about what is the post-processing that we are interested in. We are interested in the deflection and bending stress on the beam. We would also like to look at the force and moment reaction at our support A and B. Let's set up those post-processing parameters before we click solve button.

Let's start with inserting Total Deformation.

Outline > Solution (A6) > Insert > Total Deformation

Next let's insert beam tool that will enable us to look at the stresses on the beam.

Outline > Solution (A6) > Insert > Beam Tool > Beam Tool

We would also like to look at the Force Reaction at point A and B.

Outline > Solution (A6) > Insert > Probe > Force Reaction

Select Remote Displacement (which is point A) next to Boundary Condition under Details of "Force Reaction".

Do the same step for Remote Displacement 2 (point B).
Next we will like to check and see that the moment at point A and B is zero.
Outline > Solution (A6) > Insert > Probe > Moment Reaction
Select Remote Displacement (which is point A) next to Boundary Condition under Details of "Moment Reaction".

Do the same step for Remote Displacement 2 (point B).
We are done setting up all the results. Click Solve at the top menu to obtain a solution. Wait for a minute for the solution.

Go to Step 6: Results

See and rate the complete Learning Module

Go to all ANSYS Learning Modules