Setup (Physics)

Symmetry Conditions

First, let's start by declaring the symmetry conditions in the problem. Right click Model > Insert > Symmetry. This will create a symmetry folder in the outline tree. Now, right click Symmetry > Insert > Symmetry Region. Make sure the Edge Select Tool is highlighted and select the left edge above the hole. Now look to the Details View window and select Geometry > Apply. This should create a red line with a tag on the model. Ensure that under Symmetry Normal the x-axis is selected. Repeat this process to create a symmetry region for the bottom edge to the right of the hole, but this time making sure that the Symmetry Normal parameter is the y-axis.

Now, we can specify the forces on the body. Click Static Structural in the outline tree. This will bring up the Physics Menu bar in the Environment. Clock Loads > Force to specify a force. Select the right edge of the geometry and apply it in the details view window. Now we want to define the force as components, so select Define By > Components. Specify the magnitude to 50,000 lbs (Remember! We are only using 1/4 of the geometry and 1/2 of the original cross sectional area. Therefore, we can only use half of the force!).